Continue to Site

Welcome to EDAboard.com

Welcome to our site! EDAboard.com is an international Electronics Discussion Forum focused on EDA software, circuits, schematics, books, theory, papers, asic, pld, 8051, DSP, Network, RF, Analog Design, PCB, Service Manuals... and a whole lot more! To participate you need to register. Registration is free. Click here to register now.

[SOLVED] 0201 Component to component spacing

Status
Not open for further replies.

Jester

Full Member level 6
Full Member level 6
Joined
Aug 18, 2012
Messages
377
Helped
7
Reputation
14
Reaction score
7
Trophy points
1,298
Location
.
Activity points
4,754
Please see attached image

Can I place 0201 components this close to each other?

Left image is nominal footprint 0.42x0.46 pads
Right image is least footprint 0.32x0.36 pads



0201.png
 

It depends on your board fab and assy shops..

4 thou is standard outer gap for high end cost boards and 2 thou is a premium for board shops.
or 0.1mm std. high end.

Board Shop DFM rules may increase quote costs based on solder yields to these gaps, depending on their experience.

Consult with purchasing then suppliers.
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
Yes you can, these components are used on very dense boards I have used the IPC-7351 least footprint and had the placement outlines touching and had no problems with assembly or re-work.
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
Yes you can do this, But if the component assembly or rework is in hand soldering means doing repeatedly will be an issue. Whereas if it is machine assembly it should give you no problems.
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
It is OK.
Nothing worried for manufacturing and saasembling.
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
The only issue that I see is if these components are resistors dissipating near to its rated limits, due to reduction of the effective area designated to heat flowing from each one.
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
I agree with all above posts. My only warning is - if you are assembling the boards using a standard stencil, you may want to deviate from the standard 5-mil steel and reduce to a 4-mil or 3-mil. Even if paste is applied to each pad properly, the surface tension during reflow will cause a bit of movement. The risk is that you will end up with a solder bridge, which is the worst to fix on 0201's due to their size.
Also note that many assembly companies want some amount of space between components - not between the pads but between the outside of components, as pick and place machines all place within tolerance. You don't want to have one resistor placed a degree or two off and have it bumped off the pads, causing a ton of rework later.
 
In most cases, assembly houses will assemble PCB's using IPC-A-610 as a standard for quality control. In IPC-A-610, three classes are defined;

  • Class 1
  • Class 2
  • Class 3

This standard does not define the distance between to components but defines the allowable overhang of a component.
This allowable overhang determines the minimum distance between the two components. If you are planning series production of the design
you should take these values into account.


overhang.jpg
 
  • Like
Reactions: Jester and FvM

    FvM

    Points: 2
    Helpful Answer Positive Rating

    Jester

    Points: 2
    Helpful Answer Positive Rating
I would kick my assembler from here to Kathmandu if any components were that far off the pads, though I must admit out of millions of the little buggers placed over the years I have only seen them that bad twice....
The problem is with todays tight designs and copper flooded everywhere there is a chance of shorts, which is what happened in one of the cases where the comp was off the pad...........
 
  • Like
Reactions: Jester

    Jester

    Points: 2
    Helpful Answer Positive Rating
Status
Not open for further replies.

Part and Inventory Search

Welcome to EDABoard.com

Sponsor

Back
Top