$freq while using AC analysis to access lookup table

[NikosTS]

Hello all,
I have saved in a table the response of a filter. The table contains 2 columns; the first contains the frequency and the second the corresponding magnitude.
I am building a model that will instantly "read" the value of the frequency during an AC analysis and using that value will find the corresponding magnitude through the table.

My thought was using something like $table_model( $freq, "table_link.dat") and assigning that value to the output, but it doesnt seem to work. Actually it seems like the only value of frequency is 0Hz.

Any ideas?

Thank you in advance

[FvM]

Forgot to mention the circuit analysis tool.

[pancho_hideboo]

My thought was using something like $table_model( $freq, "table_link.dat")

If you mean Verilog-A, $freq is not available in Verilog-A.

https://www.edaboard.com/showthread.php?373837#6

[NikosTS]

Thank you both for the replies.

Forgot to mention the circuit analysis tool.

I use Spectre if that is what you mean.

- - - Updated - - -

If you mean Verilog-A, $freq is not available in Verilog-A.

https://www.edaboard.com/showthread.php?373837#6

Yes I am using verilogA to model a filter.
Is there any other way to search a table using frequency as the input?

[pancho_hideboo]

Use spectre primitive, nport.

If you use Keysight ADSsim, use DAC(Data Access Component).

https://www.edaboard.com/showthread.php?364412/page2#23

[NikosTS]

Use spectre primitive, nport.

If you use Keysight ADSsim, use DAC(Data Access Component).

https://www.edaboard.com/showthread.php?364412/page2#23

Thank you pancho, nport is indeed a way to associate frequency with magnitude. But it cannot be "translated" in VerilogA.
Is there a way to only use VerilogA in order to manipulate the sweeped frequency and get the wanted magnitude?

[pancho_hideboo]

Is there a way to only use VerilogA

If you insist on Verilog-A, instantiate spectre’s primitive nport in Verilog-A.

https://designers-guide.org/forum/Ya...m=1574240440#2

Other possibility is “deriv(ac_stim(1))/(M_TWO_PI)”.

I don’t know whether it works as independent variable for table_model().

[NikosTS]

If you insist on Verilog-A, instantiate spectre’s primitive nport in Verilog-A.

https://designers-guide.org/forum/Ya...m=1574240440#2

Other possibility is “deriv(ac_stim(1))/(M_TWO_PI)”.

I don’t know whether it works as independent variable for table_model().

Hello and thank you for the reply.
Instantiating the nport in VerilogA seems like a very good way to get the response I want. However, I can only connect the ports by order and not by name.
Specifically:
I want to instantiate an nport with 2 ports and NO common reference. The instance will have 4 pins : p1,m1,p2,m2 (at least in schematic editor ).
My VerilogA model has 4 pins also : INP,INN,OP,ON and I want to connect port (p1 with INP) , (m1 with INN) , (p2 with OP), (m2 with ON).

My code works and simulates correctly when I instantiate the nport as :
nport #(params) NPORT0(INP,INN,OP,ON )
but produces an error when I try to instantiate it as:
nport #(params) NPORT0(.p1(INP),.m1(INN),.p2(OP),.m2(ON) ) .

Any ideas on this?

[pancho_hideboo]

Compare CDF parameter and spectre -h nport.

Or simply use gnd node in Verilog-A.
Ground node declaration.

[NikosTS]

Compare CDF parameter and spectre -h nport.

Or simply use gnd node in Verilog-A.
Ground node declaration.

Indeed the corresponding CDF parameters were not the same as the pins of the nport.
For anyone's interest : pins p1,p2,p3... etc must be instantiated as port names t1,t2,t3... and pins m1,m2,m3.... as b1,b2,b3...

[pancho_hideboo]

`include "constants.vams"
`include "disciplines.vams"

module my_freq(out);
output out;
voltage out;

electrical gnd;
ground gnd;

voltage hoge;

analog begin
   V(hoge) <+ ac_stim();
   V(out) <+ abs( ddt( V(hoge) ) ) / `M_TWO_PI;
end //analog

endmodule

Try this code.
You can get analysis frequency value in Verilog-A.
Also I showed gnd node definition in Verilog-A.

nport #(params) NPORT0(.t1(INP),.b1(gnd),.t2(OP),.b2(gnd) )

[pancho_hideboo]

Correction.

`include "constants.vams"
`include "disciplines.vams"

module my_freq(out);
output out;
voltage out;

electrical gnd;
ground gnd;

voltage aho, boke;

analog begin
   V(aho) <+ ac_stim();
   V(boke) <+ ddt( V(aho) ) / `M_TWO_PI;
   V(out) <+ abs( V(boke) );
end //analog

endmodule

[NikosTS]

Correction.

`include "constants.vams"
`include "disciplines.vams"

module my_freq(out);
output out;
voltage out;

electrical gnd;
ground gnd;

voltage aho, boke;

analog begin
   V(aho) <+ ac_stim();
   V(boke) <+ ddt( V(aho) ) / `M_TWO_PI;
   V(out) <+ abs( V(boke) );
end //analog

endmodule

Hello pancho thank you for the reply,
I havent had the time to test that piece of code but I am not sure if it will help me anyway. The nport way works really well until now!